Wall Thickness Guidelines for Machined Parts

Wall thickness is the design rule that comes back to bite the most often, because it looks invisible on a solid model and only shows up as chatter, deflection, or a cracked part on the machine. A designer raises a thin pocket, the CAM system cuts it, and the wall flexes away from the cutter, leaving a barrel shape that fails inspection. Machined walls are not cast walls and they are not printed walls. They have to survive a rotating tool pushing against them with real force. Here are the minimums and the logic behind them.

Why thin walls move on the machine

When an end mill cuts a side wall, it pushes the wall outward by a fraction of a millimeter. On a 3 mm thick aluminum wall standing 20 mm tall, that push bows the wall, the tool cuts a shallow groove on the pass, and the wall springs back — leaving the wall thinner in the middle than at the ends. This is not a machine problem; it is stiffness. The stiffness of a rectangular wall scales with the cube of its thickness, so halving the thickness drops stiffness to an eighth. That is why a wall that looks fine on screen suddenly chatters once it is taller than about ten times its thickness. The wall thickness design guide we wrote earlier lays out these ratios with diagrams.

Safe minimums by material

Numbers differ by material because stiffness and heat differ. In aluminum (6061, 7075), a wall of 1.5 to 2 mm machines cleanly up to about 25 mm tall; below 1.2 mm you are in thin-wall territory and need light cuts and support. In steel, which is stiffer but heavier to cut, 1.5 mm works as a practical floor, and stainless wants closer to 2 mm because it work-hardens under the tool. In plastics, 1.5 mm is a comfortable minimum and 1 mm is possible on supported, short walls — but plastics deflect and melt more than metal, so they need sharper tools and lighter feeds. For copper and brass, 1.5 mm holds fine; for magnesium, which is soft and gummy at the cutting edge, keep walls above 2 mm to avoid tearing.

Height-to-thickness and pocket depth

The ratio that matters is height over thickness, not thickness alone. A 2 mm wall that is 6 mm tall is no problem. The same 2 mm wall standing 30 mm tall will chatter. As a working rule, keep walls under a height-to-thickness ratio of 10:1 for steady machining, and treat anything above 15:1 as a thin-wall project that needs fixturing, light passes, and often a sacrificial support. Pocket depth follows a similar logic: a pocket deeper than three times the tool diameter forces long, slender end mills that deflect, so either widen the pocket or step the corner radius up. Internal corners carry the tool radius too — a pocket corner needs at least R0.5 to R3 depending on tool size, and sharp corners drive tiny tools that break. The internal corner rules cover that side of the design.

Design moves that save the wall

You do not have to thicken every wall to make it work. Ribs and bosses transfer load without adding weight, but they follow the same minimums: a rib thinner than 1.5 mm just chatters. If a wall must be thin, support it — machine in a symmetric order so stress stays balanced, use a sacrificial backing or soft jaws around a thin ring, and take climb milling light passes instead of one heavy hog. Leave a finish stock of 0.1 to 0.2 mm on thin walls and take two finishing passes rather than one heavy one. On parts that will be anodized or plated, remember the coating builds on every surface; a wall you sized at the minimum before plating may end up too thin after 15 micrometers of anodize on each side. Our DFM checklist runs through these rules before you send the model.

What to ask yourself before you release the model

Run three checks on every thin feature. Can a standard end mill reach the bottom of this pocket without deflecting? Does this wall have something supporting it at the top and bottom? And did you leave coating stock on surfaces that will be finished? Most wall failures trace back to a model imported from casting or printing, where thin webs were free and nobody reworked them for cutting. If the part genuinely needs a 0.8 mm shell, plan it as a thin-wall machining job, budget the extra setups and finishing passes, and tell the shop up front. Thin-wall work is not impossible — it just stops being free once the cutting tool shows up. The thin-wall machining guide goes deeper into the strategies that hold tolerance on slender parts.

⚙

Ready to Start Your CNC Project?

Get a free quote within 24 hours. ISO 9001 certified, 20+ years experience, low-volume friendly from 1 piece.

Get a Quote